BOM - Excluding Referenced Items (CAXA) - Don't toggle on and off "Include in BOM"

[Malcolm Crowe]

By default, all Parts and Assemblies within the 3D Scene should have "Include in BOM" selected (within the Properties Browser), as you normally want these to be included in a BOM. However, there are some exceptions, such as Construction Items (like Layout Sketches) and Reference Parts (like existing Parts or a Building etc...). For these items you would deselect "Include in BOM" when you create them. However, if the Referenced Parts have other 2D drawings referencing them (which might be the case with externally linked parts), DO NOT deselect "Include in BOM" for these Items, as doing so will affect those other drawings as well.

In the attached video I demonstrate some options for excluding Referenced Items from the BOM in your 2D Drawing. This is specifically regarding CAXA DRAFT, but most of what is demonstrated is applicable to IRONCAD DRAWING (ICD) as well.

Option 1: Within the CAXA BOM deselect the "Display" option.

Option 2: Within the 3D Scene create a "Configuration" in which the Referenced Parts are "Suppressed". Then set the BOM to reference that specific "Configuration" while the Generated Views reference a different "Configuration".

Option 3: Within the 3D Scene, place any "Reference Parts" within a specific "Referenced Parts" Assembly. Then in the Properties Browser of that Assembly select "Treat as Part", and then deselect "Include in BOM".

Option 4: This is a variation of Option 3 above. Within the 3D Scene, place any "Reference Parts" within a specific "Referenced Parts" Assembly. Then in the Properties Browser of that Assembly select "Treat as Part", and leave "Include in BOM" selected. Then in the BOM of CAXA deselect "Display" for that one Item. This option allows the "Item Number" tool to be used for labelling these Referenced Parts within the drawing as well, without being listed in the BOM.

Malcolm

Edited March 11, 2023 by Malcolm Crowe